Choosing a beam element

The Euler-Bernoulli beam elements use cubic interpolation functions, which makes them reasonably accurate for cases involving distributed loading along the beam. Therefore, they are well suited for dynamic vibration studies, where the d'Alembert (inertia) forces provide such distributed loading.

The cubic beam elements are written for small-strain, large-rotation analysis. They may not be appropriate for torsional stability problems due to the approximations in the underlying formulation and cannot be used in analyses involving very large rotations (of the order 180°); quadratic or linear beam elements should be used instead.

The Euler-Bernoulli beam elements use a consistent mass formulation. Rotary inertia for twist around the beam axis is the same as for Timoshenko beams. For details, see Mass and inertia for Timoshenko beams. Any additional inertia defined for these elements (see Adding inertia to the beam section behavior for Timoshenko beams) is ignored.

The effective transverse shear stiffness of the section of a shear flexible beam is defined in Abaqus as

where ${\overline{K}}_{\alpha 3}$ is the section shear stiffness in the $\alpha$-direction; $f_p^{\alpha }$ is a dimensionless factor used to prevent the shear stiffness from becoming too large in slender beam elements; $K_{\alpha 3}$ is the actual shear stiffness of the section; and $\alpha =1,2$ are the local directions of the cross-section. The $K_{\alpha 3}$ have units of force.

The dimensionless factors $f_p^{\alpha }$ are always included in the calculation of transverse shear stiffness and are defined as

where l is the length of the element, A is the cross-sectional area, $I_{\alpha \alpha }$ is the inertia in the $\alpha$-direction, $SCF$ is the slenderness compensation factor (with a default value of 0.25), and $\xi$ is a constant of value 1.0 for first-order elements and 10⁻⁴ for second-order elements.

For meshed cross-sections the above expressions change to

You can define the $K_{\alpha 3}$ or $K_{\alpha \beta }^{ts}$ as described below. If you do not specify them, they are defined by

or

where G is the elastic shear modulus or moduli and A is the cross-sectional area of the beam section. Temperature and field variable dependencies of G are not taken into account when calculating $K_{\alpha 3}$ and $K_{\alpha \beta }^{ts}$. The shear factor k (Cowper, 1966) is defined as:

When a beam section definition integrated during the analysis is used (see Using a beam section integrated during the analysis to define the section behavior), G is calculated from the elastic material definition used with the section. When a general beam section definition is used (see Using a general beam section to define the section behavior), you provide G as part of the beam section data.

BEAM SECTION
TRANSVERSE SHEAR STIFFNESS

BEAM GENERAL SECTION
TRANSVERSE SHEAR STIFFNESS

Property module: beam section editor: Section integration: During analysis: Stiffness: toggle on Specify transverse shear

Property module: beam section editor: Section integration: Before analysis: Stiffness, toggle on Specify transverse shear

Abaqus provides finite axial strain, shear flexible beams with linear and quadratic interpolations. Their formulation is described in Beam element formulation.

Element types B21, B31, B31OS, PIPE21, PIPE31, and their hybrid equivalents use linear interpolation. These elements are well suited for cases involving contact, such as the laying of a pipeline in a trench or on the seabed or the contact between a drill string and a well hole, and for dynamic versions of similar problems (impact).

Element types B22, B32, B32OS, PIPE22, PIPE32, and their hybrid equivalents use quadratic interpolation.

The linear Timoshenko beam elements use a lumped mass formulation by default. The quadratic Timoshenko beam elements in Abaqus/Standard use a consistent mass formulation, except in dynamic procedures in which a lumped mass formulation with a 1/6, 2/3, 1/6 distribution is used. For details, see Mass and inertia for Timoshenko beams. The quadratic Timoshenko beam elements in Abaqus/Explicit use a lumped mass formulation with a 1/6, 2/3, 1/6 distribution.

BEAM SECTION, LUMPED=NO

BEAM GENERAL SECTION, LUMPED=NO

Property module: beam section editor: Section integration: During analysis: Stiffness tabbed page: toggle on Use consistent mass matrix formulation

Property module: beam section editor: Section integration: Before analysis: Stiffness tabbed page: toggle on Use consistent mass matrix formulation

By default, the exact (anisotropic with displacement-rotation coupling) rotary inertia is used for Timoshenko beams. Optionally, an uncoupled isotropic approximation to the rotary inertia can be used. See Rotary inertia for Timoshenko beams for further details.

The exception to this rule is the static procedure with automatic stabilization (see Static stress analysis), where the mass matrix for Timoshenko beams is always calculated assuming isotropic rotary inertia, regardless of the type of rotary inertia specified for the beam section definition (see Rotary inertia for Timoshenko beams).

In some structural applications the beam element may be a one-dimensional approximation of a structure with complex cross-sectional geometry and mass distribution. In such a cross-section there may be inertia contributions that represent heavy machinery, cargo loaded in a ship compartment, fluid-filled ballast tanks, or any other mass distributed along the length of the beam that is not part of the beam's structural stiffness. In such cases you can define additional mass and rotary inertia associated with the beam section properties. Multiple masses per unit length (with location other than the origin of the beam cross-section) and rotary inertias per unit length can be specified. Mass proportional damping (alpha or composite damping) associated with this additional inertia can also be specified. Abaqus will use the mass weighted average (based on the material damping and the added inertial damping) for the element mass proportional damping. See Material damping for details.

When a beam is fully or partially submerged, the effect of the surrounding fluid can be modeled as an additional distributed inertia on the beam. See Additional inertia due to immersion in fluid for details.

When modeling beams in space, a further consideration arises from the possible warping of the beam's cross-section under torsional loading. For all but circular sections the beam's cross-section will deform out of its original plane when subject to torsion. This warping deformation will modify the shear strain distribution throughout the section.

Open sections will typically twist very easily if warping is not prevented, especially if the walls that form the beam section are thin. Constraint of this warping at certain points along the beam (such as where the beam is built into some other member, Figure 1, or into a wall) is then a major determinant of the beam's overall torsional response.

Figure 1. Intersection of open section beams.

Element types B31OS, B32OS (and their “hybrid” equivalents) have the warping magnitude, w, as a degree of freedom at each node; they are available only in Abaqus/Standard. In these elements Abaqus/Standard assumes that the warping of the cross-section follows a certain pattern as a function of position in the cross-section (Abaqus will calculate this warping pattern if you have specified a standard library section or an “arbitrary” section): only the warping magnitude varies with position along the beam's axis. These elements are meant for the analysis of thin-walled open sections in which warping constraints play a role and the axial strains due to warping cannot be neglected. Examples of such open sections that may warp in this fashion are the I-section and any open arbitrary section. In the other beam element types warping is considered unconstrained and any axial stress due to warping is neglected; torsional behavior will not be represented adequately when these element types are used with thin-walled, open sections.

In general, the warping magnitude can be continuous only when the beam axis is continuous through a node and the beam cross-section is the same on both sides of the node. Thus, if open-section members intersect at a node (such as the cross-member of a vehicle chassis abutting a longitudinal member, Figure 1), separate nodes may have to be used for the intersecting members with different axial directions and appropriate constraints must be chosen for the warping amplitudes in each member at this point. The choice of these constraints is a matter of detail of the local construction. For example, if the joint is reinforced, warping may be prevented; therefore, degree of freedom 7 should be fully constrained with a boundary condition on the appropriate members at the joint.

The pipe elements in Abaqus assume a hollow circular section. The internal stress caused by internal or external pressure loading in the pipe is included in these elements so that on the pipe cross-section a point under tension will have different yield than a point under compression (Figure 2), thus causing an asymmetry in the section's response to inelastic bending. Two formulations are available for pipe elements in Abaqus. The thin-walled pipe formulation assumes constant hoop stress across the cross-section and neglects the radial stress, whereas thick-walled pipes (available only in Abaqus/Standard) allow the hoop and radial stress components to vary across the cross-section.

Figure 2. Yield behavior in thin-walled PIPE elements.

The hoop stress in thin-walled pipe elements is computed as the average stress in equilibrium with the internal and external pressure loading on the pipe section. For the thin-walled formulation, an integration rule with one point through the thickness suffices to obtain an accurate solution.

For thick-walled pipes, the hoop stress and radial stress variation under applied internal and/or external pressure are calculated using Lamé’s equations. The constitutive calculations at each material point take into account the imposed hoop and radial stress values to determine the structural response. A two-dimensional integration rule is used for thick-walled pipes to capture the effect of stress variation across the section accurately.