From the main menu bar, select
.
A Create Connector Section dialog box appears.
Enter a section name. For more information about naming objects, see
Using basic dialog box components.
Choose one of the following connection categories:
Choose Assembled/Complex to use either
predefined combinations of basic connection types or complex connection types.
Click the arrow next to the Assembled/Complex
type text field, and select the desired connection type from the
list that appears.
Choose Basic to use translational and
rotational connection types.
If desired, click the arrow next to the
Translational type text field, and select the connection
type from the list that appears.
If desired, click the arrow next to the Rotational
type text field, and select the connection type from the list that
appears.
You can select one translational type, one rotational type, or one
translational and one rotational type to define the connector section.
Abaqus/CAE
displays the available and constrained components of relative motion
(CORM) for the connection type that you have
selected. In addition, you can click
 to see a schematic drawing of the connection type along with the
Abaqus
idealization of the connection.
For a description of assembled, complex, and basic connection types,
see
Connection types.
Click Continue.
The connector section editor appears.
Note:
You can display help on a particular editor feature by selecting
from the main menu bar and then clicking the
editor feature of interest. For more information on editor features, see
Using the connector section editors.
To edit the connection type, click
 to the right of the connection type to display the connector
section type editor. Select the connection type as described above. You must
delete all behaviors from the editor before you can edit the connection type.
On the Behavior Options tabbed page, you can add,
delete, and change behaviors as follows:
- Adding
behaviors
Click Add on the right side of the editor to
display a list of available behaviors. Select the behaviors needed to define
your connector section. You can define multiple behaviors of the same type for
some behaviors. When you select a behavior, its name appears in the
Behavior Options list, and data fields associated with the
behavior appear in the data area in the bottom half of the editor. Use the data
fields to enter information for the currently selected behavior. For more
information, see
Using the connector section editors.
- Deleting
behaviors
In the Behavior Options list, select the behavior
that you want to delete, and click Delete on the right
side of the editor. This procedure removes the behavior from both the behavior
options list and the connector section definition.
- Changing
behavior data
In the Behavior Options list, select the behavior
whose data you want to change. When the data fields associated with the
behavior appear in the bottom half of the window, change the information that
you have entered for the behavior as desired.
On the Table Options tabbed page, you can specify
behavior settings for the regularization (Abaqus/Explicit
analyses only) and the extrapolation of tabular data for all of the behavior
options in a connector section. Alternatively, you can specify behavior
settings for individual behavior options. The Table
Options button is available on the Behavior
Options tabbed page for selected behavior options. Behavior settings
for individual behavior options take precedence over the connector section
behavior settings. For more information, see
Specifying behavior settings for tabular data,
and
Defining connector behavior using tabular data.
Specify behavior settings on the Table Options
tabbed page as follows:
- In the Regularization portion of the page,
specify the settings for the regularization of tabular data in an
Abaqus/Explicit
analysis. By default,
Abaqus/Explicit
regularizes the data into tables that are defined in terms of even intervals of
the independent variables.
- If you want to regularize tabular data, specify the error
tolerance.
Choose Use default to use the default
value of 0.03.
Choose Specify, and enter a value for the
error tolerance.
- In the Extrapolation portion of the page,
specify the method for the extrapolation of tabular data. The data points that
you enter make up a nonlinear curve in the constitutive space. By default,
Abaqus
extrapolates the dependent variables as constant values that correspond to the
end points of the curve outside the specified range of the independent
variables.
Choose Constant to use constant
extrapolation of the dependent variables outside the specified range of the
independent variables.
Choose Linear to use linear extrapolation
of the dependent variables outside the specified range of the independent
variables.
The Section Data tabbed page becomes available
for the following connection types:
For the Flow-Converter or
Retractor connection type, enter the following section
data:
- Node b material flow
scaling factor
Enter the scaling factor, ,
associated with the material flow at node b. Node
b refers to the second point of a wire used to model a
connector in
Abaqus/CAE.
The default value is 1.
For more information, see
FLOW-CONVERTER
and
RETRACTOR.
For the Slip Ring connection type, enter the
following section data:
- Mass per unit reference
length
Enter the mass per unit reference length of belt material.
- Contact
angle around node b
The contact angle refers to the angle made by the belt wrapping
around node b. Node b refers to the
second point of a wire used to model a connector in
Abaqus/CAE.
For an
Abaqus/Standard
analysis you must specify the contact angle directly. For an
Abaqus/Explicit
analysis you can specify the contact angle directly, or you can let
Abaqus
calculate the contact angle based on the configuration of your model:
To let
Abaqus
calculate the contact angle, select Compute.
To specify the contact angle directly, select
Specify and enter the contact angle in degrees.
For more information, see
SLIPRING.
Click OK to save the data and to exit the
editor.
|
tool in the
Interaction module
toolbox.