Element section variables

The output variables listed below are available in Abaqus/Standard.

SF

.dat: yes  .fil: yes  .odb Field: yes  .odb History: yes  

All section force and moment components.

SFn

.dat: yes  .fil: no  .odb Field: no  .odb History: yes  

Section force per unit width of component n ($n=1,2,3,4,5$ for conventional shells; $n=1,2,3,4,5,6$ for continuum shells; $n=1,2,3$ for beams).

SMn

.dat: yes  .fil: no  .odb Field: no  .odb History: yes  

Section moment per unit width of component n ($n=1,2,3$).

SORIENT

.dat: no  .fil: no  .odb Field: yes  .odb History: no  

Composite shell section orientations.

BIMOM

.dat: yes  .fil: no  .odb Field: no  .odb History: yes  

Bimoment of beam cross-section. Available only for open-section beam elements.

ESF1

.dat: yes  .fil: yes  .odb Field: yes  .odb History: yes  

Effective axial force for beams and pipes subjected to pressure loading. Available for all stress/displacement procedure types except response spectrum and random response.

SSAVG

.dat: yes  .fil: yes  .odb Field: yes  .odb History: no  

All average shell section stress components.

SSAVGn

.dat: yes  .fil: no  .odb Field: no  .odb History: yes  

Average shell section stress component n ($n=1,2,3,4,5,6$).

SE

.dat: yes  .fil: yes  .odb Field: yes  .odb History: yes  

All section strain, curvature change, and twist components.

SEn

.dat: yes  .fil: no  .odb Field: no  .odb History: yes  

Section strain component n ($n=1,2,3,4,5,6$ for shells; $n=1,2,3$ for beams).

SKn

.dat: yes  .fil: no  .odb Field: no  .odb History: yes  

Section curvature change or twist n ($n=1,2,3$).

BICURV

.dat: yes  .fil: no  .odb Field: no  .odb History: yes  

Bicurvature of beam cross-section. Available only for open-section beam elements.

MAXSS

.dat: yes  .fil: yes  .odb Field: no  .odb History: no  

Maximum axial stress on the section. (This variable can be used with the following types of general beam section definitions: standard library cross-sections, linear generalized cross-sections, or meshed cross-sections with specified output section points. If the output section points are specified, the MAXSS output will be the maximum of the stresses at the user-specified points.)

COORD

.dat: yes  .fil: yes  .odb Field: yes  .odb History: yes  

Coordinates of the section point. These are the current coordinates if the large-displacement formulation is being used.

STH

.dat: yes  .fil: yes  .odb Field: yes  .odb History: yes  

Section thickness (current thickness for SAX1, SAX2, SAX2T, S3/S3R, S4, S4R, SAXA1N, SAXA2N, and all membrane elements if the large-displacement formulation is used; initial thickness for all other cases).

SVOL

.dat: yes  .fil: yes  .odb Field: yes  .odb History: yes  

Integrated section volume. (Not available for eigenfrequency extraction, eigenvalue buckling prediction, complex eigenfrequency extraction, or linear dynamics procedures. Available only for continuum and structural elements not using general beam or shell section definitions.)

SPE

.dat: yes  .fil: yes  .odb Field: yes  .odb History: yes  

All generalized plastic strain components. Available only for inelastic nonlinear response in a general beam section.

SPEn

.dat: yes  .fil: no  .odb Field: no  .odb History: yes  

Generalized plastic strain component n ($n=1,2,3,4$). Representing axial plastic strain, curvature change about the local 1-axis, curvature change about the local 2-axis, and twist of the beam. Available only for inelastic nonlinear response in a general beam section.

SEPE

.dat: yes  .fil: yes  .odb Field: yes  .odb History: yes  

All equivalent plastic strains. Available only for inelastic nonlinear response in a general beam section.

SEPEn

.dat: yes  .fil: no  .odb Field: no  .odb History: yes  

Equivalent plastic strain component n ($n=1,2,3,4$). Representing axial plastic strain, curvature change about the local 1-axis, curvature change about the local 2-axis, and twist of the beam. Available only for inelastic nonlinear response in a general beam section.