Whole element variables

You can request whole element variable output to the results or output database file.

The following topics are discussed:

Related Topics
Element output
Element output

The output variables listed below are available in Abaqus/Explicit.

ELEN
.fil: yes  .odb Field: yes  .odb History: yes  

All energy magnitudes in the element.

ELSE
.fil: no  .odb Field: yes  .odb History: yes  

Total elastic strain energy in the element (includes energy in transverse shear deformation in shells).

ELCD
.fil: no  .odb Field: yes  .odb History: yes  

Total energy dissipated in the element by viscoelastic deformation. (Not supported for hyperelastic and hyperfoam material models with linear viscoelasticity.)

ELPD
.fil: no  .odb Field: yes  .odb History: yes  

Total energy dissipated in the element by rate-independent and rate-dependent plastic deformation.

ELVD
.fil: no  .odb Field: yes  .odb History: yes  

Total energy dissipated in the element by viscous effects. This includes bulk viscosity and material damping.

ELASE
.fil: no  .odb Field: yes  .odb History: yes  

Total “artificial” strain energy in the element. This includes hourglass energy and drilling stiffness energy in shells.

ELIHE
.fil: no  .odb Field: yes  .odb History: yes  

Internal heat energy in the element.

ELDMD
.fil: no  .odb Field: yes  .odb History: yes  

Total energy dissipated in the element by damage.

ELDC
.fil: no  .odb Field: yes  .odb History: yes  

Total energy dissipated in the element by distortion control.

ELEDEN
.fil: no  .odb Field: yes  .odb History: no  

All element energy density components.

ESEDEN
.fil: no  .odb Field: yes  .odb History: no  

Total elastic strain energy density in the element.

EPDDEN
.fil: no  .odb Field: yes  .odb History: no  

Total energy dissipated per unit volume in the element by rate-independent and rate-dependent plastic deformation.

ECDDEN
.fil: no  .odb Field: yes  .odb History: no  

Total energy dissipated per unit volume in the element by viscoelasticity.

EVDDEN
.fil: no  .odb Field: yes  .odb History: no  

Total energy dissipated per unit volume in the element by viscous effects.

EASEDEN
.fil: no  .odb Field: yes  .odb History: no  

Total “artificial” strain energy density in the element (energy associated with constraints used to remove singular modes, such as hourglass control).

EIHEDEN
.fil: no  .odb Field: yes  .odb History: no  

Internal heat energy density in the element.

EDMDDEN
.fil: no  .odb Field: yes  .odb History: no  

Total energy dissipated per unit volume in the element by damage.

EDCDEN
.fil: no  .odb Field: yes  .odb History: no  

Total energy dissipated per unit volume in the element by distortion control.

EDT
.fil: yes  .odb Field: yes  .odb History: yes  

Element stable time increment.

EMSF
.fil: yes  .odb Field: yes  .odb History: yes  

Element mass scaling factor.

STATUS
.fil: yes  .odb Field: yes  .odb History: yes  

Status of element (material failure with progressive damage, shear failure model, tensile failure model, porous failure criterion, brittle failure model, Johnson-Cook plasticity model, and VUMAT). The status of an element is 1.0 if the element is active, 0.0 if the element is not.

EVOL
.fil: no  .odb Field: yes  .odb History: no  

Current element volume. (Only available for continuum and structural elements not using general beam or shell section definitions.)

NFORC
.fil: no  .odb Field: yes  .odb History: yes  

Forces at the nodes of an element from both the hourglass and the regular deformation modes of that element (negative of the internal forces in the global coordinate system).

GRAV
.fil: no  .odb Field: yes  .odb History: no  

Uniformly distributed gravity load.

SBF
.fil: no  .odb Field: yes  .odb History: no  

Stagnation body force.

BF
.fil: no  .odb Field: yes  .odb History: no  

Uniformly distributed body force, including viscous body force.

EDMICRTMAX
.fil: no  .odb Field: yes  .odb History: no  

Whole shell element maximum damage initiation output among all of the layers, all of the damage initiation criteria, and for fully integrated elements across all of the integration points.

This output variable is the same as DMICRTMAX output for solid and beam elements but complements the DMICRTMAX output variable for composite shell elements because it extracts the maximum damage initiation across all of the layers.

This output variable generates four element output quantities as follows:

EDMICRTMAXVAL outputs the maximum damage initiation value in the entire element.

EDMICRTLAYER outputs the layer number in which the maximum damage initiation value occurred.

EDMICRTTYPE outputs a value that represents the damage initiation criteria type that reached the maximum value in the element, as described in the DMICRTMAX output variable description.

EDMICRTINTP outputs the integration point number for which the maximum damage value occurred. For reduced-integration elements, the output value is one.

The maximum damage initiation output values are retained across the requested output frames until a higher maximum damage initiation value is computed.